3.7. Results Information Routines
3.7.1. Function dspiqr (Getting Information About Nodal Results)
*deck,dspiqr
function dspiqr (node,key)
c *** primary function: get information about nodal results
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c node (int,sc,in) - node number
c = 0 - return information based on the setting of key
c > 0 - return result mask for given node
c key (int,sc,in) - key as to the information needed
c when node > 0 and key = 1 --> return result mask for given node
c when node = 0 and key = DB_MAXRECLENG --> return maximum record length (dp words)
c NOTE: only supported with database (not object)
c when node = 0 and key = any other value --> return number of calculated displacements in model
c output arguments:
c dspiqr (int,func,out) - the returned value of dspiqr is based on setting of node/key
3.7.2. Function dspget (Getting a Nodal Result from the Database)
*deck,dspget
function dspget (node,ndf,idf,value)
c *** primary function: get a nodal result from the data base
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c node (int,sc,in) - node number
c ndf (int,sc,in) - number of results requested
c idf (int,ary(ndf),in) - reference number for the DOF: (1-32)
c UX = 1, UY = 2, UZ = 3, ROTX= 4, ROTY= 5, ROTZ= 6, AX = 7, AY = 8
c AZ = 9, VX =10, VY =11, VZ =12, GFV1=13, GFV2=14, GFV3=15, WARP=16
c CONC=17, HDSP=18, PRES=19, TEMP=20, VOLT=21, MAG =22, ENKE=23, ENDS=24
c EMF =25, CURR=26, SP01=27, SP02=28, SP03=29, SP04=30, SP05=31, SP06=32
c (missing entries are spares)
c output arguments:
c value (dp,ar(ndf),out) - result values
3.7.3. Subroutine dspput (Storing a Result at a Node)
*deck,dspput
subroutine dspput (node,ndf,idf,value)
c *** primary function: store a result at a node.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c node (int,sc,in) - node number
c ndf (int,sc,in) - number of results to be stored
c idf (int,ary(ndf),in) - reference number for the DOF: (1-32)
c value (dp,ar(ndf),in) - displacement values
c output arguments: none
3.7.4. Subroutine dspdel (Deleting a Result at a Node)
*deck,dspdel
subroutine dspdel (node,ndf,idf)
c *** primary function: delete a result at a node
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c node (int,sc,in) - node number. (0 to delete DOF at all
c nodes)
c ndf (int,sc,in) - number of DOFs to delete (0 to delete
c all DOFs)
c idf (int,ar(*),in) - reference number for the DOF: (1-32)
c UX = 1, UY = 2, UZ = 3, ROTX= 4, ROTY= 5, ROTZ= 6, AX = 7, AY = 8
c AZ = 9, VX =10, VY =11, VZ =12, GFV1=13, GFV2=14, GFV3=15, WARP=16
c CONC=17, HDSP=18, PRES=19, TEMP=20, VOLT=21, MAG =22, ENKE=23, ENDS=24
c EMF =25, CURR=26, SP01=27, SP02=28, SP03=29, SP04=30, SP05=31, SP06=32
c output arguments: none
3.7.5. Function emsiqr (Getting Information About an Element's Miscellaneous Summable
Data)
*deck,emsiqr
function emsiqr (ielem,key)
c *** primary function: get information about element misc summable data
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about misc summed data records
c ielem > 0 - return number of misc summed
c data items for this element
c (record length)
c = 0 - return maximum number of misc
c summed data items on any
c element (max record length)
c = DB_NUMDEFINED - return total number of misc summed data
c items defined in model
c output arguments:
c emsiqr (int,func,out) - the returned value of emsiqr is based on
c setting of key
3.7.6. Function emsget (Getting an Element's Miscellaneous Summable Data)
*deck,emsget
function emsget (ielem,value)
c *** primary function: get element misc summable data.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c emsget (int,func,out) - status of element.
c = 0 - element is undefined
c > 0 - number of data items returned
c value (dp,ar(*),out) - element misc summed data.
c NOTE: the contents of this record is element
c dependent. See SMISC on ETABLE command
3.7.7. Subroutine emsput (Storing an Element's Miscellaneous Summable Data)
*deck,emsput
subroutine emsput (ielem,nval,value)
c *** primary function: store misc. summable data for an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - number of values to be stored
c value (dp,ar(nval),in) - the misc summed data values
c output arguements: none
c NOTE: the contents of this record is element
c dependent. See SMISC on ETABLE command
3.7.8. Subroutine emsdel (Deleting an Element's Miscellaneous Summable Data)
*deck,emsdel
subroutine emsdel (ielem)
c *** primary function: delete element misc summable data
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.9. Function enfiqr (Getting Information About Element Nodal Forces)
*deck,enfiqr
function enfiqr (ielem,key)
c *** primary function: get information about element nodal forces
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element nodal forces
c ielem > 0 - return number of element nodal
c forces for this element
c (record length)
c = 0 - return maximum number of element
c nodal forces on any element
c (max record length)
c = DB_NUMDEFINED - return total number of element nodal
c forces defined in model
c output arguments:
c enfiqr (int,func,out) - the returned value of enfiqr is based on
c setting of key
3.7.10. Function enfget (Getting an Element's Nodal Forces)
*deck,enfget
function enfget (ielem,value)
c *** primary function: get element nodal forces.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c enfget (int,func,out) - status of element.
c = 0 - element has no nodal forces
c > 0 - number of nodal forces returned
c value (dp,ar(*),out) - element nodal forces
3.7.11. Subroutine enfput (Storing an Element's Nodal Forces)
*deck,enfput
subroutine enfput (ielem,nval,value)
c *** primary function: store nodal force results at an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c NOTE: There may be a maximum of 3 sets of
c nodal forces in the record: static
c forces, inertia forces, and damping forces
c value (dp,ar(nval),in) - nodal force results
c output arguments: none
3.7.12. Subroutine enfdel (Deleting an Element's Nodal Forces)
*deck,enfdel
subroutine enfdel (ielem)
c *** primary function: delete element nodal forces data
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.13. Function ensiqr (Getting Information About an Element's Nodal Stresses)
*deck,ensiqr
function ensiqr (ielem,key)
c *** primary function: get information about element nodal stresses
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element nodal stresses
c ielem > 0 - return number of element nodal
c stresses for this element
c (record length)
c = 0 - return maximum number of element
c nodal stresses on any element
c (max record length)
c = DB_NUMDEFINED - return total number of element
c nodal stresses defined in model
c output arguments:
c ensiqr (int,func,out) - the returned value of ensiqr is based on
c setting of key
3.7.14. Function ensget (Getting an Element's Nodal Stresses)
*deck,ensget
function ensget (ielem,value)
c *** primary function: get element nodal stresses.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c ensget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of nodal stresses
c returned
c value (dp,ar(*),out) - element nodal stresses
c NOTE: Stresses at each corner node in the order
c X, Y, Z, XY, YZ, XZ, S1, S2, S3, SI, SE
c For solid elements, stresses at each
c corner node
c For shell elements, stresses at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c stresses for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Stresses for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c stresses for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LS
c item of ETABLE command.
3.7.15. Subroutine ensput (Storing Nodal Stresses at an Element)
*deck,ensput
subroutine ensput (ielem,nval,value)
c *** primary function: store nodal stresses at an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (11*nnod*nface)
c value (dp,ar(nval),in) - the stress values
c output arguments: none
c NOTE: Stresses at each corner node in the order
c X, Y, Z, XY, YZ, XZ, S1, S2, S3, SI, SE
c For solid elements, stresses at each
c corner node
c For shell elements, stresses at each
c corner node (first top surface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c stresses for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Stresses for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c stresses for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LS
c item of ETABLE command.
3.7.16. Subroutine ensdel (Deleting an Element's Nodal Stresses)
*deck,ensdel
subroutine ensdel (ielem)
c *** primary function: delete element nodal stresses
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.17. Function esfiqr (Getting Information About Element Surface Stress Data)
*deck,esfiqr
function esfiqr (ielem,key)
c *** primary function: get information about element surface stress data
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about surface stress
c ielem > 0 - return number of surface stresses on this
c element (rec length)
c = 0 - return maximum number of surface stresses
c on any element (max rec length)
c = DB_NUMDEFINED - return the number of surface stresses
c defined in model
c output arguments:
c esfiqr (int,func,out) - the returned value of esfiqr is based on
c setting of key
3.7.18. Function esfget (Getting Element Surface Stress Data)
*deck,esfget
function esfget (ielem,value)
c *** primary function: get element surface stress data.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c esfget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of values returned
c value (dp,ar(*),out) - element surface stress data.
3.7.19. Subroutine esfput (Storing Element Surface Stress Data)
*deck,esfput
subroutine esfput (ielem,nval,value)
c *** primary function: store surface stresses for an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (19 * number of stress faces)
c There is a max of 2 stress faces
c value (dp,ar(nval),in) - the values
c output arguments: none
3.7.20. Subroutine esfdel (Deleting an Element's Surface Stress Data)
*deck,esfdel
subroutine esfdel (ielem)
c *** primary function: delete element surface stress data
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.21. Function engiqr (Getting Information About an Element's Energies)
*deck,engiqr
function engiqr (ielem,key)
c *** primary function: get information about element energies
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element energies
c ielem > 0 - return number of element energies on
c this element (rec length)
c = 0 - return maximum number of element
c energies on any element
c (max rec length)
c = DB_NUMDEFINED - return the number of element energies
c defined in model
c output arguments:
c engiqr (int,func,out) - the returned value of engiqr is based on
c setting of key
3.7.22. Function engget (Getting an Element's Energies)
*deck,engget
function engget (ielem,value)
c *** primary function: get element energies.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c engget (int,func,out) - status of element.
c = 0 - element undefined
c = MAXENG+1 - energies returned (see in echprm.inc)
c value (dp,ar(MAXENG+1),out) - volume and energies
c value(1) = volume of element
c (2) = stiffness energy
c (3) = artificial hourglass energy
c (4) = kinetic energy
c (5) = plastic energy
c (6) = creep energy
c (7) = stabilization energy
c (8) = strain energy density
c (9) = thermal energy
c (10) = viscous regularization energy for CZM
c (11) = sparse (future friction energy)
c (12) = damping energy
c (13) = external work by element load
c (14) = stiffness energy amplitude
c (15) = kinetic energy amplitude
c (16) = stiffness energy peak
c (17) = kinetic energy peak
c (18) = intermediate result for stif. energ. amplitude
c in harmonic analysis 1
c (19) = intermediate result for kin. energ. amplitude
c in harmonic analysis 1
c (20) = intermediate result for stif. energ. amplitude
c in harmonic analysis 2
c (21 = MAXENG+1) = intermediate result for kin. energ. amplitude
c in harmonic analysis 2
3.7.23. Subroutine engput (Storing an Element's Energies and Volume)
*deck,engput
subroutine engput (ielem,nval,value)
c *** primary function: store volume and energies for an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values to be stored
c must be MAXENG (see in echprm.inc)
c value (dp,ar(MAXENG+1),in) - volume and energies
c value(1) = volume of element
c (2) = stiffness energy
c (3) = artificial hourglass energy
c (4) = kinetic energy
c (5) = plastic energy
c (6) = creep energy
c (7) = stabilization energy
c (8) = strain energy density
c (9) = thermal energy
c (10) = viscous regularization energy for CZM
c (11) = sparse (future friction energy)
c (12) = damping energy
c (13) = external work by element load
c (14) = stiffness energy amplitude
c (15) = kinetic energy amplitude
c (16) = stiffness energy peak
c (17) = kinetic energy peak
c (18) = intermediate result for stif. energ. amplitude
c in harmonic analysis 1
c (19) = intermediate result for kin. energ. amplitude
c in harmonic analysis 1
c (20) = intermediate result for stif. energ. amplitude
c in harmonic analysis 2
c (21 = MAXENG+1) = intermediate result for kin. energ. amplitude
c in harmonic analysis 2
c output arguments: none
3.7.24. Subroutine engdel (Deleting an Element's Energies)
*deck,engdel
subroutine engdel (ielem)
c *** primary function: delete element energies
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.25. Function egriqr (Getting Information About an Element's Nodal Gradients)
*deck,egriqr
function egriqr (ielem,key)
c *** primary function: get information about element nodal gradients
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about nodal gradients
c for ielem > 0 - return number of nodal gradients on
c this element (record length)
c = 0 - return maximum number of nodal
c gradients on any element
c (maximum record length)
c = DB_NUMDEFINED - return the number of nodal gradients defined
c in model
c output arguments:
c egriqr (int,func,out) - the returned value of egriqr is based on
c setting of key
3.7.26. Function egrget (Getting an Element's Nodal Gradients)
*deck,egrget
function egrget (ielem,value)
c *** primary function: get element nodal gradients.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c egrget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of nodal gradients
c returned
c value (dp,ar(*),out) - element nodal gradients
c Note: If a coupled field, a set of
c gradients are stored in the following
c order (as available): fluid, thermal,
c electric, magnetic
c *** mpg egrget < pagend,magget<hsnget2: get elem gradient, H,
3.7.27. Subroutine egrput (Storing an Element's Nodal Gradients)
*deck,egrput
subroutine egrput (ielem,nval,value)
c *** primary function: store nodal gradients at an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (ndir*nnod*nscalr)
c value (dp,ar(nval),in) - the gradient values
c Note: If a coupled field, a set of
c gradients are stored in the following
c order (as appropriate): fluid, thermal,
c electric, magnetic
c output arguments: none
3.7.28. Subroutine egrdel (Deleting an Element's Nodal Gradients)
*deck,egrdel
subroutine egrdel (ielem)
c *** primary function: delete element nodal gradients
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.29. Function eeliqr (Getting Information About an Element's Nodal Elastic
Strains)
*deck,eeliqr
function eeliqr (ielem,key)
c *** primary function: get information about element nodal elastic strains
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about elastic strains
c ielem > 0 - return number of nodal elasic strains
c on this element (rec length)
c = 0 - return maximum number of nodal elastic
c strains on any element
c (max rec length)
c = DB_NUMDEFINED - return the number of nodal elastic strains
c defined in model
c output arguments:
c eeliqr (int,func,out) - the returned value of eeliqr is based on
c setting of key
3.7.30. Function eelget (Getting an Element's Nodal Elastic Strains)
*deck,eelget
function eelget (ielem,value)
c *** primary function: get element nodal elastic strains.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c eelget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of nodal elastic strains
c returned
c value (dp,ar(*),out) - element nodal elastic strains
c NOTE: Strains at each corner node in the order
c X, Y, Z, XY, YZ, XZ, EQV
c For solid elements, strains at each
c corner node
c For shell elements, strains at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c strains for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Strains for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c strains for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LEPEL
c item of ETABLE command.
3.7.31. Subroutine eelput (Storing an Element's Nodal Elastic Strains)
*deck,eelput
subroutine eelput (ielem,nval,value)
c *** primary function: store nodal elastic strains at an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (7*nnod*nface)
c value (dp,ar(nval),in) - nval strain values
c output arguments: none
c NOTE: Strains at each corner node in the order
c X, Y, Z, XY, YZ, XZ, EQV
c For solid elements, strains at each
c corner node
c For shell elements, strains at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c strains for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Strains for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c strains for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LEPEL
c item of ETABLE command.
3.7.32. Subroutine eeldel (Deleting an Element's Nodal Elastic Strains)
*deck,eeldel
subroutine eeldel (ielem)
c *** primary function: delete element elastic strains
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.33. Function epliqr (Getting Information About an Element's Nodal Plastic
Strains)
*deck,epliqr
function epliqr (ielem,key)
c *** primary function: get information about element nodal plastic strains
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about plastic strains
c ielem > 0 - return number of nodal plastic strains
c on this element
c (record length)
c = 0 - return maximum number of nodal plastic
c strains on any element
c (max record length)
c = DB_NUMDEFINED - return the number of nodal plastic strains
c defined in model
c output arguments:
c epliqr (int,func,out) - the returned value of epliqr is based on
c setting of key
3.7.34. Function eplget (Getting an Element's Nodal Plastic Strains)
*deck,eplget
function eplget (ielem,value)
c *** primary function: get element nodal plastic strains.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c eplget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of nodal plastic strains
c returned
c value (dp,ar(*),out) - element nodal plastic strains
c NOTE: Strains at each corner node in the order
c X, Y, Z, XY, YZ, XZ, EQV
c For solid elements, strains at each
c corner node
c For shell elements, strains at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c strains for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Strains for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c strains for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LEPPL
c item of ETABLE command.
3.7.35. Subroutine eplput (Storing an Element's Nodal Plastic Strains)
*deck,eplput
subroutine eplput (ielem,nval,value)
c *** primary function: store nodal plastic strains at a element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (6*nnod*nface)
c value (dp,ar(nval),in) - the strain values
c output arguments: none
c NOTE: Strains at each corner node in the order
c X, Y, Z, XY, YZ, XZ, EQV
c For solid elements, strains at each
c corner node
c For shell elements, strains at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c strains for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Strains for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c strains for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LEPPL
c item of ETABLE command.
3.7.36. Subroutine epldel (Deleting an Element's Nodal Plastic Strains)
*deck,epldel
subroutine epldel (ielem)
c *** primary function: delete element plastic strains
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.37. Function ecriqr (Getting Information About an Element's Nodal Creep
Strains)
*deck,ecriqr
function ecriqr (ielem,key)
c *** primary function: get information about element nodal creep strains
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about creep strains
c ielem > 0 - return number of nodal creep strains
c on this element
c (record length)
c = 0 - return maximum number of nodal creep
c strains on any element
c (max record length)
c = DB_NUMDEFINED - return the number of nodal creep strains
c defined in model
c output arguments:
c ecriqr (int,func,out) - the returned value of ecriqr is based on
c setting of key
3.7.38. Function ecrget (Getting an Element's Nodal Creep Strains)
*deck,ecrget
function ecrget (ielem,value)
c *** primary function: get element nodal creep strains.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c ecrget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of nodal creep strains
c returned
c value (dp,ar(*),out) - element nodal creep strains
c NOTE: Strains at each corner node in the order
c X, Y, Z, XY, YZ, XZ, EQV
c For solid elements, strains at each
c corner node
c For shell elements, strains at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c strains for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Strains for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c strains for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LEPCR
c item of ETABLE command.
3.7.39. Subroutine ecrput (Storing an Element's Nodal Creep Strains)
*deck,ecrput
subroutine ecrput (ielem,nval,value)
c *** primary function: store nodal creep strains at an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (6*nnod*nface)
c value (dp,ar(nval),in) - the strain values
c output arguments: none
c NOTE: Strains at each corner node in the order
c X, Y, Z, XY, YZ, XZ, EQV
c For solid elements, strains at each
c corner node
c For shell elements, strains at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c strains for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Strains for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c strains for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LEPCR
c item of ETABLE command.
3.7.40. Subroutine ecrdel (Deleting an Element's Nodal Creep Strains)
*deck,ecrdel
subroutine ecrdel (ielem)
c *** primary function: delete element creep strains
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.41. Function ethiqr (Getting Information About an Element's Nodal Thermal
Strains)
*deck,ethiqr
function ethiqr (ielem,key)
c *** primary function: get information about element nodal thermal strains
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about thermal strains
c ielem > 0 - return number of nodal thermal strains
c on this element
c (record length)
c = 0 - return maximum number of nodal thermal
c strains on any element
c (max record length)
c = DB_NUMDEFINED - return the number of nodal thermal strains
c defined in model
c output arguments:
c ethiqr (int,sc,out) - the returned value of ethiqr is based on
c setting of key
3.7.42. Function ethget (Getting an Element's Nodal Thermal Strains)
*deck,ethget
function ethget (ielem,value)
c *** primary function: get element nodal thermal strains.
c also the volumetric swelling strain
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c ethget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of nodal thermal strains
c returned
c value (dp,ar(*),out) - element nodal thermal strains
c NOTE: Strains at each corner node in the order
c X, Y, Z, XY, YZ, XZ, EQV, epswel
c For solid elements, strains at each
c corner node
c For shell elements, strains at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c strains for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Strains for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c strains for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LEPTH
c item of ETABLE command.
3.7.43. Subroutine ethput (Storing an Element's Nodal Thermal Strains)
*deck,ethput
subroutine ethput (ielem,nval,value)
c *** primary function: store nodal thermal strains at an element.
c also the volumetric swelling strain
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (7*nnod*nface)
c value (dp,ar(nval),in) - the strain values
c output arguments: none
c NOTE: Strains at each corner node in the order
c X, Y, Z, XY, YZ, XZ, EQV, epswel
c For solid elements, strains at each
c corner node
c For shell elements, strains at each
c corner node (first top durface, then
c bottom)
c For layered elements (w/KEYOPT(8)=0),
c strains for "first" layer at each
c corner node (first at the bottom
c surface of the bottom layer, then the
c top surface of the top layer).
c Strains for "second" layer at each
c corner node (first the bottom surface,
c then the top surface for the layer with
c the largest failure criteria).
c The second layer is not present if
c failure criteria were not used or are
c not appropriate
c For layered elements (w/KEYOPT(8)=1),
c strains for each layer at each corner
c node (first at the bottom surface, then
c the top surface)
c For beam elements, the contents of this
c record is element depenent. See LEPTH
c item of ETABLE command.
3.7.44. Subroutine ethdel (Deleting an Element's Thermal, Initial, and Swelling
Strains)
*deck,ethdel
subroutine ethdel (ielem)
c *** primary function: delete element thermal, initial, and
c swelling strains
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.45. Function euliqr (Getting Information About an Element's Euler Angles)
*deck,euliqr
function euliqr (ielem,key)
c *** primary function: get information about element euler angles
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element euler angles
c ielem > 0 - return number of euler angles on this
c element
c (record length)
c = 0 - return maximum number of euler angles
c on any element
c (max record length)
c = DB_NUMDEFINED - return the number of element euler angles
c defined in model
c output arguments:
c euliqr (int,func,out) - the returned value of euliqr is based on
c setting of key
3.7.46. Function eulget (Getting an Element's Nodal Euler Angles)
*deck,eulget
function eulget (ielem,value)
c *** primary function: get element nodal euler angles.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c eulget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of euler angle values
c returned
c value (dp,ar(*),out) - element euler angles
c NOTE: For lower-ordered elements, rotations
c at centroid
c For higher-ordered elements, rotations
c at each corner node
c For layered shells, rotations at each
c corner node, plus layer rotation angle
c for each layer (real constant THETA)
c For layered solids, rotation angles at
c centroid, plus layer rotation angle
c for each layer (real constant THETA)
c For surface element, no euler angles
c are saved
3.7.47. Subroutine eulput (Storing an Element's Euler Angles)
*deck,eulput
subroutine eulput (ielem,nval,value)
c *** primary function: store nodal euler angles for an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (3 * number of display nodes)
c value (dp,ar(nval),in) - the euler angle values
c output arguments: none
c NOTE: For lower-ordered elements, rotations
c at centroid
c For higher-ordered elements, rotations
c at each corner node
c For layered shells, rotations at each
c corner node, plus layer rotation angle
c for each layer (real constant THETA)
c For layered solids, rotation angles at
c centroid, plus layer rotation angle
c for each layer (real constant THETA)
3.7.48. Subroutine euldel (Deleting an Element's Euler Angles)
*deck,euldel
subroutine euldel (ielem)
c *** primary function: delete element euler angles
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.49. Function efxiqr (Getting Information About Element Fluxes)
*deck,efxiqr
function efxiqr (ielem,key)
c *** primary function: get information about element fluxes
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element fluxes
c ielem > 0 - return number of fluxes on this
c element
c (record length)
c = 0 - return maximum number of fluxes
c on any element
c (max record length)
c = DB_NUMDEFINED - return the number of element fluxes defined
c in model
c output arguments:
c efxiqr (int,func,out) - the returned value of efxiqr is based on
c setting of key
3.7.50. Function efxget (Getting an Element Flux)
*deck,efxget
function efxget (ielem,value)
c *** primary function: get element nodal fluxes.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c efxget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of nodal fluxes returned
c value (dp,ar(*),out) - element nodal fluxes
c Note: If a coupled field, a set of fluxes is
c stored in the following order (as
c available): fluid, thermal,
c electric, magnetic
3.7.51. Subroutine efxput (Storing an Element's Fluxes)
*deck,efxput
subroutine efxput (ielem,nval,value)
c *** primary function: store nodal fluxes at an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c (ndir*nnod*nscalr)
c value (dp,ar(nval),in) - the flux values
c output arguments: none
c Note: If a coupled field, a set of fluxes is
c stored in the following order (as
c available): fluid, thermal,
c electric, magnetic
3.7.52. Subroutine efxdel (Deleting Element Fluxes)
*deck,efxdel
subroutine efxdel (ielem)
c *** primary function: delete element nodal fluxes
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.53. Function elfiqr (Getting Information About Element Local Forces)
*deck,elfiqr
function elfiqr (ielem,key)
c *** primary function: get information about elem local forces
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element local forces
c ielem > 0 - return number of local forces on this
c element
c (record length)
c = 0 - return maximum number of local forces
c on any element
c (max record length)
c = DB_NUMDEFINED - return the number of element local forces
c defined in model
c output arguments:
c elfiqr (int,func,out) - the returned value of elfiqr is based on
c setting of key
3.7.54. Function elfget (Getting an Element Local Force)
*deck,elfget
function elfget (ielem,value)
c *** primary function: get element local nodal forces.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c elfget (int,func,out) - status of element.
c = 0 - element has no local nodal forces
c > 0 - number of nodal forces returned
c value (dp,ar(*),out) - element local nodal forces.
3.7.55. Subroutine elfput (Storing an Element's Local Forces)
*deck,elfput
subroutine elfput (ielem,nval,value)
c *** primary function: store element local nodal forces.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c variable (typ,siz,intent) description
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c NOTE: There may be a maximum of 3 sets of
c nodal forces in the record: static
c forces, inertia forces, and damping forces
c value (dp,ar(nval),in) - element local nodal forces
c output arguments: none
3.7.56. Subroutine elfdel (Deleting Element Local Forces)
*deck,elfdel
subroutine elfdel (ielem)
c *** primary function: delete element local forces
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.57. Function emniqr (Getting Information About Element Miscellaneous Non-summable
Data)
*deck,emniqr
function emniqr (ielem,key)
c *** primary function: get information about element misc non-summable
c data
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element misc non-summed data
c ielem > 0 - return number of data items on this
c element
c (record length)
c = 0 - return maximum number of data items
c on any element
c (max record length)
c = DB_NUMDEFINED - return the number of element misc non-summed
c data items defined in model
c output arguments:
c emniqr (int,func,out) - the returned value of emniqr is based on
c setting of key
3.7.58. Function emnget (Getting an Element's Miscellaneous Non-summable Data)
*deck,emnget
function emnget (ielem,value)
c *** primary function: get misc non-summable data.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c emnget (int,func,out) - status of element.
c = 0 - no non-summed misc data at this
c element
c > 0 - number of data items returned
c value (dp,ar(*),out) - element misc non-summed data.
c NOTE: the contents of this record is element
c dependent. See NMISC on ETABLE command
3.7.59. Subroutine emnput (Storing an Element's Miscellaneous Non-summable Data)
*deck,emnput
subroutine emnput (ielem,nval,value)
c *** primary function: store misc. non-summable data for an element.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c value (dp,ar(nval),in) - the misc. non-summed data items
c output arguments: none
c NOTE: the contents of this record is element
c dependent. See NMISC on ETABLE command
3.7.60. Subroutine emndel (Deleting an Element's Miscellaneous Non-summable Data)
*deck,emndel
subroutine emndel (ielem)
c *** primary function: delete element misc non-summable data
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.61. Function ecdiqr (Getting Information About Element Current Densities)
*deck,ecdiqr
function ecdiqr (ielem,key)
c *** primary function: get information about element current densities
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element current densities
c ielem > 0 - return number of current densities on
c this element
c (record length)
c = 0 - return maximum number of current
c densities on any element
c (max record length)
c = DB_NUMDEFINED - return the number of element current
c densities defined in model
c output arguments:
c ecdiqr (int,func,out) - the returned value of ecdiqr is based on
c setting of key
3.7.62. Function ecdget (Getting an Element Current Density)
*deck,ecdget
function ecdget (ielem,value)
c *** primary function: get calculated element current densities.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c ecdget (int,func,out) - status of element.
c = 0 - element has no current densities
c > 0 - number of calculated element
c current densities
c value (dp,ar(*),out) - calculated element current densities.
c NOTE: current densities are in the order
c X, Y, Z
3.7.63. Subroutine ecdput (Storing an Element's Current Densities)
*deck,ecdput
subroutine ecdput (ielem,nval,value)
c *** primary function: store calculated element current densities
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c value (dp,ar(nval),in) - calculated element current densities.
c output arguments: none
c NOTE: current densities are in the order
c X, Y, Z
3.7.64. Subroutine ecddel (Deleting Element Current Densities)
*deck,ecddel
subroutine ecddel (ielem)
c *** primary function: delete element current densities
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.65. Function enliqr (Getting Information About Element Nonlinear Tables)
*deck,enliqr
function enliqr (ielem,key)
c *** primary function: get information about element nonlinear tables
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about element nonlinear tables
c ielem > 0 - return number of nonlinear tables for
c this element
c (record length)
c = 0 - return maximum number of nonlinear
c tables for any element
c (max record length)
c = DB_NUMDEFINED - return the number of element nonlinear
c tables defined in model
c output arguments:
c enliqr (int,func,out) - the returned value of enliqr is based on
c setting of key
3.7.66. Function enlget (Getting Element Nonlinear Tables)
*deck,enlget
function enlget (ielem,value)
c *** primary function: get element nonlinear tables.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c enlget (int,func,out) - status of element.
c = 0 - nonlinear tables undefined
c > 0 - number of nonlinear tables defined
c value (dp ,ar(n),out) - the element nonlinear tables.
c NOTE: Nonlinear data at each node are in the
c order SEPL, SRAT, HPRES, EPEQ, PSV,
c PLWK, and 4 spares
c For beam elements, the contents and
c number of information is element
c dependent. See NLIN on ETABLE
c command
3.7.67. Subroutine enlput (Storing an Element's Nonlinear Tables)
*deck,enlput
subroutine enlput (ielem,n,temp)
c *** primary function: store element nonlinear tables
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c n (int,sc,in) - number of element nonlinear table values
c temp (dp ,ar(6),in) - element nonlinear table,etc.
c output arguments: none.
c NOTE: Nonlinear data at each node are in the
c order SEPL, SRAT, HPRES, EPEQ, PSV,
c PLWK, and 4 spares
c For beam elements, the contents and
c number of information is element
c dependent. See NLIN on ETABLE
c command
3.7.68. Subroutine enldel (Deleting Element Nonlinear Tables)
*deck,enldel
subroutine enldel (ielem)
c *** primary function: delete element nonlinear tables
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
3.7.69. Function ehciqr (Getting Information About Calculated Element Heat
Generations)
*deck,ehciqr
function ehciqr (ielem,key)
c *** primary function: get information about calculated elem heat generations
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number (or zero, see below)
c key (int,sc,in) - key as to the information needed
c = 1 - return info about calculated element heat gens
c for ielem > 0 - return number of heat gens for
c this element
c (record length)
c = 0 - return maximum number of heat gens
c for any element
c (max record length)
c = DB_NUMDEFINED - return the number of calculated element heat
c generations defined in model
c output arguments:
c ehciqr (int,func,out) - the returned value of ehciqr is based on
c setting of key
3.7.70. Function ehcget (Getting a Calculated Element Heat Generation)
*deck,ehcget
function ehcget (ielem,value)
c *** primary function: get calculated element heat generations.
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c output arguments:
c ehcget (int,func,out) - status of element.
c = 0 - element undefined
c > 0 - number of calculated element
c heat generations
c value (dp,ar(*),out) - calculated element heat generations.
3.7.71. Subroutine ehcput (Storing an Element's Calculated Heat Generations)
*deck,ehcput
subroutine ehcput (ielem,nval,value)
c *** primary function: store calculated element heat generations
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c nval (int,sc,in) - the total number of values
c value (dp,ar(nval),in) - calculated element heat generations.
c output arguments: none
3.7.72. Subroutine ehcdel (Deleting Element Calculated Heat Generations)
*deck,ehcdel
subroutine ehcdel (ielem)
c *** primary function: delete calculated element heat generations
c *** Notice - This file contains ANSYS Confidential information ***
c input arguments:
c ielem (int,sc,in) - element number
c = 0 - delete for all defined elements
c output arguments: none.
